7.5 Verifying Hole Position
Key Takeaways
Position uses the basic geometry in the drawing datum reference frame. Record units and the location of the evaluated feature.
For the stated circular-section problem, double the radial center displacement to express a diametrical result. Assess the controlled length and the actual fitting method.
A qualified functional gage evaluates a specified boundary as an attribute check. Other requirements such as limits of size still need the prescribed inspection.
7.5 Verifying Hole Position
Plan the measurement from the frame
Read the feature control frame together with the basic dimensions, size limits, part section and any projection or pattern notes. Figure out how the nominal axis is placed and oriented. Check whether the position tolerance uses RFS, MMC or LMC, and distinguish the condition of the toleranced hole from material-boundary modifiers on datum references. Identify the controlled extent before selecting access from one or both sides.
Set up the datum references, respecting their precedence and permitted movement. A CMM routine should measure enough of each datum feature and use the appropriate fit for the specified geometry, constraints and standard. For a physical fixture, verify the actual references seat as designed. Confirm the released drawing revision, correct feature and data origin. A similar fixture used for machining can position the work differently from the drawing’s specified measurement reference.
Understand the diametrical result in a simple case
For a perfect circular section whose true center is basic X and Y, find signed differences and in the established datum coordinates. The radial center displacement is . A zone centered at the basic location must have twice that radius as its diameter to contain the observed center. Thus:
This equation describes a section-center result. With an ideal straight axis whose endpoints are known, check the extent of the axis. A real bore can tilt, taper, have an unusual form or have different calculated centers from different fitting methods. Use the actual controlled feature and evidence required by the callout.
Worked case with a tilted axis
A drawing calls for a ⌀0.016 in position tolerance at RFS. The basic center is X = 1.250 in and Y = 0.750 in relative to A, B and C, with an ideal axis normal to A. In this teaching case the hole is an ideal round cylinder with a straight centerline, and the given centers are on that line at the two ends of its controlled length. The intersections of the tilted centerline with planes perpendicular to nominal are the points used below.
| Station | Measured center | Differences from the basic center | Required zone diameter at station |
|---|---|---|---|
| Entry | X 1.253, Y 0.746 in | +0.003, −0.004 in | 2 × 0.005 = 0.010 in |
| Exit | X 1.256, Y 0.742 in | +0.006, −0.008 in | 2 × 0.010 = 0.020 in |
The entry would look good by itself. The exit lies outside the permitted 0.008 in radius, so the controlled axis fails in this idealized calculation. The difference is a potential sign of tilt that the midpoint or an entry-only check could hide. Verify actual surface sampling and the fitting routine rather than imposing this synthetic result on an arbitrary measured bore.
Choose boundary or measured evidence as specified
For an MMC hole, the drawing can be verified with a qualified functional fixture that represents the position boundary and the specified datum references. For example, a hole with 0.500 in MMC and position ⌀0.010 at MMC has a theoretical virtual-condition boundary of 0.490 in at the basic location. The physical gage must follow its design and applicable gaging tolerances. A standalone pin that fits the hole cannot evaluate its position relative to other features. A pass against a qualified functional gage is a boundary result. It does not establish the actual position value or automatically check every size limit. Follow the inspection plan for a separate size check and use its rule for acceptance near a limit.
Consider a replacement gage pin that has the right nominal diameter but lacks an approved calibration record. The pin’s label alone does not establish the position boundary or the fixture location. Use the qualified gage and preserve the identity of its datum-contact hardware. If an assembly includes several basic hole locations and the drawing makes them a pattern, verify those relationships in the common setup before using independent pass results to release the pattern.
Record the evidence suited to the decision. A variable result can help diagnose shift or tilt before adjusting a toolpath or fixture. A binary gage result helps screen for a specified boundary but does not identify which part dimension caused rejection. Confirm gage condition and the approved setup before making a process change.
ASME Y14.5-2018 position rules, ASME Y14.43 gage and fixture principles and Hexagon datum fitting
In a circular-section example the offset from basic is +0.005 in in X and −0.012 in in Y. What diameter of zone would just include this center?
0.013 in
0.017 in
0.026 in
0.034 in
Why does checking only the entry center of a hole fail to verify axis position over the controlled length?
Axis tilt can produce a larger offset deeper in the hole
The first depth always has the greatest error
The basic coordinates apply only at the datum face
A location tolerance always applies only to diameter
What additional check can be needed after an MMC position functional gage accepts a hole pattern?
Change the program based on the measured Cpk of the gage
Use the gage result as the numerical position of every hole
Increase the bonus tolerance on the drawing
Verify the separate hole size limits using the approved method
What does a loose pin that fits one hole establish by itself?
The hole’s location relative to datum B
Some clearance for that pin under the insertion conditions
That every hole in the pattern meets the datum-oriented boundary
The position value in the part reference frame
Sections you finish are checked off in the contents.