6.1 Feature Control Frames and Datum References
Key Takeaways
Use the standard and revision invoked on the drawing. These examples use ASME Y14.5-2018.
The datum feature is on the part. A true geometric counterpart establishes a theoretically exact datum, and a physical simulator realizes it for practical measurement.
Six independent degrees of freedom describe rigid-body position and orientation. Which ones a datum constrains depends on geometry and precedence.
A change from a rectangular location zone to a circular cross-section is a design decision. Any comparison of their areas must name the size and fit assumptions.
6.1 Feature Control Frames and Datum References
Read the callout as a whole
ASME Y14.5 specifies how drawings and models communicate dimensions and geometric tolerances. Use the edition referenced in the released product definition. The examples here use ASME Y14.5-2018, reaffirmed in 2024. A geometric tolerance controls a stated characteristic such as position, flatness, orientation or runout. To interpret it, identify the feature controlled, how the zone is shaped and located, and what references are required.
For a hole, consider the training callout [⌖] [⌀0.010 Ⓜ] [A] [B] [C] next to a separate diameter size requirement. Read the link from the frame to the hole first. Then read across the compartments.
| Field | Meaning in this example |
|---|---|
| ⌖ | Position is the characteristic being controlled. |
| ⌀0.010 | A diametrical position zone of 0.010 in at the stated condition. The boxed basic dimensions establish the true location. |
| Ⓜ following 0.010 | Maximum material condition applies to the toleranced hole. For this internal feature, MMC is its smallest permitted size. |
| A, B, C | Datum features referenced in primary, secondary and tertiary precedence. Each is identified elsewhere on the part drawing. |
A diameter symbol and a material condition modifier appear when applicable. A form control such as flatness of a surface can specify a tolerance without a datum reference. If a material boundary symbol follows a datum reference letter on an applicable feature, it governs that datum reference. The same circled M following the tolerance value applies to the controlled feature. Read its location in the frame before applying a size-based rule. Section 6.3 of this guide develops material conditions and the position calculation.
Separate the part feature, the datum and the measurement hardware
A datum feature is a selected actual feature of the part, such as a planar base or a hole surface. The datum reference letter tells you which feature to use. The true geometric counterpart is the theoretically perfect geometry used to establish the datum from that real feature under the specified rules. The datum is the exact plane, axis, line, point or combination obtained from that counterpart. The counterpart of a qualifying hole, for example, can be an ideal cylinder, with its axis serving as the datum.
A physical datum feature simulator is a practical device used to establish a simulated datum. A suitable surface plate can simulate the reference for a planar base. A suitable fitted gage can realize an axis for a hole when it satisfies the specified boundary, engagement and precedence. On a CMM, the fitting and alignment method must realize the drawing’s datum requirements. Arbitrarily probing three points on a surface does not generally verify the correct datum, and one setup method cannot be inferred from the number of letters in a frame.
Determine what remains free
Three translations and three rotations are possible for a rigid part. A primary planar datum feature on a horizontal base constrains height and the two tilts in the seated setup. Two orthogonal side references can then define the three remaining coordinates. In the rectangular three-plane example, a secondary side constrains one in-plane translation and rotation about the base normal. A tertiary end establishes the last translation.
This example illustrates the logic behind a well-seated 3-2-1 arrangement. The number of constrained coordinates depends on the referenced feature and its place in the frame. A primary cylindrical datum feature referenced at regardless of material boundary can establish an axis and constrain two transverse translations and two tilts. Motion along and rotation about the axis remain free unless other references constrain them. Apply precedence to the specific controlled characteristic rather than assuming every frame fully locates a part.
Compare zone geometry under a declared assumption
Consider only the planar location of points. A coordinate limit of ±0.005 in on each of two orthogonal directions creates a square 0.010 in on each side. Its area is 0.000100 in². The corner lies in from the nominal center.
If a designer intends to compare a circular cross-section using the same largest radial error, the radius is 0.007071 in and the diameter is about 0.01414 in. The circle has an area of about 0.0001571 in², roughly 57.1% larger. The circle includes points outside the square along the coordinate axes. If the approved limit instead requires a diameter of 0.010 in, that circle has a smaller area of about 0.00007854 in² and excludes the corners. Neither comparison selects the drawing tolerance. The functional mating conditions, feature sizes, datum setup, and required axis or surface relationship decide what zone to specify and how to inspect it.
ASME Y14.5-2018, Sections 3, 6 and 7, and ASME GD&T interpretation topics
A square coordinate zone is ±0.005 in along each axis. Its circumscribed circle gives about 57% more area. What assumption makes this comparison valid?
The circular diameter equals the width of the square
Both zones allow the same maximum radial distance from the nominal center
The change is automatically approved by any fastener assembly
The circle is inscribed inside the square
For the stated horizontal planar primary datum, which independent degrees of freedom are constrained?
Three translations
Two transverse translations and two tilts
Translation normal to the plane and rotation about two axes in the plane
Translation along and rotation around the plane normal only
A hole is identified as datum feature B. What can serve as datum B when the specified datum is the hole axis?
The exact axis established from the appropriate true geometric counterpart
The irregular physical surface of the drilled hole itself
Any indicator contact point on the hole’s edge
The letter B, treated as a material condition
In a feature control frame, where does a circled M for maximum material condition of the toleranced feature appear?
After the last datum letter
Before the geometric characteristic symbol
Inside the boxed basic location dimension
After the tolerance value in its compartment
Sections you finish are checked off in the contents.