3.6 Create and Check a CNC Setup Sheet

Key Takeaways

  • A setup sheet identifies the approved program and drawing, machine, fixture, stock, work origin, tool assemblies and first-piece checks.

  • Match the documented origin and register to both the program and the active machine offsets. The same G54 program coordinates can move to different physical positions after a setup change.

  • Record clearance and tool assembly conditions along with nominal dimensions. An elevated retract only clears an obstacle when the complete tool and holder envelope is clear.

  • Resolve a print, program, fixture or tool mismatch before motion, then document the correction and recheck the affected operations.

Last updated: November 2026

3.6 Create and Check a CNC Setup Sheet

The NIMS CNC Mill Programming, Setup, and Operations crosswalk calls for developing and interpreting setup sheets. A setup sheet explains how to turn the program’s coordinates and tool calls into a physical setup. It supports the drawing and the approved program. It should let another qualified person repeat or check the setup from the recorded references.

Build the Sheet from the Job

Start with the part number, drawing revision, operation number and approved program revision. Name the intended machine or control and attach the correct tool list and fixture illustration. A program file name reused from an older revision can be misleading. Use the identification method specified by the shop, and verify the approved revision before running it.

Next specify the stock size, material and orientation. Show how the part rests and locates in the fixture. Give each required clamp or stop a clear location and identify any areas the cutter cannot cross at the normal retract height. Include how to locate the part zero, which offset register to enter, and whether the program uses inch or metric mode. Record the tool assembly as a cutter and a holder with required reach or stickout, plus the matching tool and offset numbers.

A CAM-generated setup sheet can help by listing program and tool information. Verify its entries against the actual machine, fixture and installed tool assemblies. A picture from the wrong operation may show a part loaded in the opposite orientation.

Worked Setup: Two Drilled Locations

The following is a training example for operation 10 on an inch-programmed Haas mill. The print revision is C and the controlled program release is 04. The part is held on parallels, with the low-X and low-Y faces defining XY zero and the faced top defining Z0. The program calls G54, then uses Tool 2 with H02 for drilling.

Sheet fieldExample entryDirect check
Program and printOperation 10, program O01234 release 04; drawing revision CMatch the approved file and drawing to the job traveler.
Fixture and stockDesignated vise on parallels; long edge parallel to XConfirm the workpiece sits against the specified locating surfaces and matches the setup image.
Work offsetG54, low-X and low-Y faces, faced top Z0, inchesCompare the sheet to program G54 and G20 and the physical origin.
Tool and offsetTool 2 is the listed drill assembly; H02 is its lengthMatch pocket/tool and the measured assembly. Check reach and holder clearance.
Hole locations and clearanceTwo locations separated by a clamp; highest obstruction at work Z+0.600 inVerify the actual return plane used before crossing, and the cutter-and-holder envelope.
First-piece checksHole size, location, and any drawing-specific inspection before repeat productionChoose appropriate gages and record against the referenced drawing revision.

Suppose the setup sheet says the clamp is clear at R+0.400 in, while the actual clamp reaches +0.600 in. The drill tip would be 0.200 in below the top of that obstruction if it crossed the clamp at R. Pause the setup. Look at the code that controls the return from the first hole, and establish a proven crossing height for the actual fixture and tool assembly before authorizing motion. Record the approved change, then check the toolpath and the first affected part. Adjusting the speed of a path through an obstruction does not provide clearance.

Handle an Inconsistent Handoff

Consider a different discrepancy. The release record lists revision C, but the loaded sheet has revision B and identifies the fixed jaw as the Y reference. The current drawing uses the opposite face for the origin shown in the approved setup. Even if the screen shows G54, the content of that register can be wrong for the new job. Resolve the drawing and setup instruction with the person responsible for the release, then verify the physical reference and revise the sheet or loaded files as appropriate.

At the end of setup, trace the first few program blocks against the sheet. Verify the selected fixture and units, the loaded tool and offset, the approach and return clearances, and the programmed stop or inspection points. Record what changed so the next operator can reproduce the checked setup under the shop’s procedures. This connects the document to the manufactured part and the inspection record.

Sources: NIMS CNC mill competency crosswalk, Haas part setup, and Autodesk manufacturing setup sheets.

Test Your Knowledge

The next mill setup uses the approved program’s G54, but the old sheet identifies the opposite Y face as zero. What should the operator do before motion?

A

Use the old G54 value because the program calls G54.

B

Switch to machine coordinates and run the program.

C

Resolve the setup revision, locate the current specified face, and verify the stored G54 offset.

D

Compensate by changing drill length H02.

Test Your Knowledge

A clamp reaches Z+0.600 in and the tip’s planned crossing height is R+0.400 in. How far below the clamp top is the tip?

A

0.200 in

B

0.400 in

C

0.600 in

D

1.000 in

Test Your Knowledge

The approved program loads Tool 2 and uses H02. A backup cutter is measured in a longer holder. What should you verify first?

A

Only that the backup fits the magazine.

B

Only that the parts have the same drawing number.

C

Only that the spindle starts in the right direction.

D

The assembly identity, measured length, linked H register, reach and clearance for the intended path.

Sections you finish are checked off in the contents.