3.4 CNC Control Modes & Program Verification (Dry Run, Single Block)

Key Takeaways

  • On a Haas mill, use EDIT for program changes, MEMORY for a selected program, MDI for temporary program blocks, and HANDLE JOG for manual positioning.

  • Haas Graphics mode shows a toolpath while the machine stays still. A physical dry run involves actual motion and must follow the machine and shop procedures.

  • During prove-out, check the entire programmed path against stock, fixture and holder geometry. One Z offset or percentage override cannot assure clearance.

  • Distance To Go reports the remaining commanded axis travel for the active move. Check its reference and direction against the known setup before continuing.

  • Feed Hold can leave the Haas spindle running. Emergency Stop is a control function, and hazardous servicing requires the shop’s verified energy isolation procedure.

Last updated: November 2026

CNC Control Modes and Program Verification

Prove out a new program any time the setup, offsets, or code could put the tool, holder or fixture in a different place. Use the drawings, setup sheet and tool list together. A correct program can still crash if the physical vise or tool stickout differs from the setup assumed by the programmer. The controls here illustrate a Haas mill. Check the manual for the actual machine, control and software before running motion.

Control Modes

ControlTypical Haas mill useWhat to check
EDITCreate and edit programsVerify the revision and which program you have selected for execution. A controller can support background editing, so editing does not establish a safe state.
MEMORYRun a selected memory programCheck the starting block, work offset, tool and overrides.
MDI (Manual Data Input)Execute temporary commands without creating a saved production programInputs can command real motion. Read the complete temporary program before executing it.
HANDLE JOGManually position an axisCheck the selected axis, sign, jog increment and clearance first.
ZERO RETURN / POWER UPReference axes under the applicable procedureReferencing may move the axes. Clear the travel path before starting.

A machine-coordinate command such as G53 depends on the machine coordinate system already established at reference. Use the documented reference-return controls to establish that reference. A restart is a separate decision from a reference return.

Proving a Job

  1. Check the setup against the program. Match the part revision, stock, vise or fixture and clamp positions to the setup sheet. Confirm the active work coordinate system, loaded tools, offset assignments, and tool lengths. Review rapid and retract moves as carefully as cutting moves.
  2. Run a graphics check. On a Haas mill, Graphics mode displays commanded motion while the machine stays still. Use it to look for an unexpected direction, an incomplete retract, or a wrong part origin. Confirm real-world clearances independently. The fixture and holder on the machine may have geometry the display does not represent.
  3. Verify real motion under the shop procedure. A dry run or air cut that moves the machine can still collide. Establish a verified clearance for each relevant toolpath, including fixture-to-fixture travel, canned-cycle retracts and tool changes. Check machine travel limits. Keep safeguards functional and follow the control-specific instructions. Use permitted single-block operation and rapid or feed overrides appropriate to the procedure. Some settings or operations restrict what can be overridden.
  4. Inspect the first machined part. Compare measured results against the current print and control plan. Record corrections and recheck the first piece after a change before continuing production.

Worked Clearance Check

The top of the stock is work Z = 0.000 in. A clamp beside it reaches work Z = +0.750 in. The program attempts a straight horizontal move across that clamp with the tip of the tool at work Z = +0.500 in. The tool tip is 0.250 in below the top of the clamp. The move needs correction even though it clears the stock. Choosing a higher retract also requires checking the cutter and holder envelope, the clamp’s width, the programmed path, and the machine’s Z travel. The same issue can occur when a canned cycle returns only to the R plane between holes.

Interpreting Distance To Go

On the Haas Position display, Distance To Go is the remaining travel to the commanded position. For a paused straight move, if the work-coordinate Z position is +0.250 in and the block target is Z = −0.500 in, the remaining commanded Z travel is −0.750 in. If the verified clearance to a protected fixture surface in the path is only 0.250 in, continuing the full move would overtravel that gap by 0.500 in. Keep motion stopped, determine why the command and setup disagree, and correct and recheck the setup before restarting. A displayed distance describes motion in the active control state. It cannot detect a clamp or validate a tool length.

Feed Hold and Emergency Stop

On the Haas mill, Feed Hold normally stops programmed rapid and feed moves. The spindle continues to run. Tapping cycles, dwell timers and auxiliary axes have specific limitations described in the control manual. Use the appropriate emergency control if there is immediate danger. The Emergency Stop button stops machine activity including axis motion, spindle and tool changer and turns off the coolant pump. Hazardous energy can remain present. An authorized employee must apply and verify the shop’s energy-control procedure when required for servicing or clearing a jam.

After an emergency stop, keep the machine stopped, alert the responsible person and resolve the hazard using the applicable procedure. Follow the manufacturer’s instructions for the fault and the shop’s authorization for restart. Establish the machine reference again only if the recovery procedure calls for it and the path is clear. Before restarting, verify the tool, work offset, tool length compensation, other modal states and approach motion from the restart point.

Sources: Haas control pendant, Haas mill operation, and OSHA hazardous-energy control.

Test Your Knowledge

Which Haas mill mode lets a trained operator run a temporary command without creating a saved production program?

A

EDIT Mode

B

MEM / AUTO Mode

C

Manual Data Input (MDI) Mode

D

REF RETURN Mode

Test Your Knowledge

Stock top is Z = 0.000 in. A clamp reaches Z = +0.750 in, and a programmed horizontal path crosses it at Z = +0.500 in. What does the first prove-out check show?

A

The tip clears the clamp by 0.250 in along the crossing path.

B

The tip is 0.250 in below the clamp top on the crossing path.

C

The tip is level with the clamp top because Z uses stock top.

D

The tip must clear the clamp because both positions are above stock top.

Test Your Knowledge

On a Haas mill during a paused linear move, what does Distance To Go show?

A

The total operating time remaining until the program finishes

B

The remaining commanded axis travel to the active block’s target

C

The total distance from the current tool position back to Machine Zero (G53)

D

The cumulative linear wear on the active cutting tool tip

Test Your Knowledge

A Haas mill was stopped after a fixture problem. A jam must be cleared and hazardous energy could cause injury. What should happen before work on the jam?

A

Press Cycle Start and use Feed Hold at the next block.

B

Release Emergency Stop and jog the axis out of the jam.

C

Keep the machine stopped and have an authorized employee apply and verify the shop’s energy-control procedure before clearing the jam.

D

Switch to EDIT and hold the Emergency Stop button down while clearing debris.

Sections you finish are checked off in the contents.