8.1 Position Tolerancing Fundamentals, True Position, & Coordinate Conversions

8.1 Position Tolerancing Fundamentals, True Position, & Coordinate Conversions

Quick Answer: In ASME Y14.5-2009 Section 7.2, position is a geometric tolerance that defines a zone within which the center, axis, or center plane of a feature of size is permitted to vary from its theoretically exact location (true position). True position is established by basic dimensions originating from an established Datum Reference Frame (DRF). Specifying a cylindrical position tolerance zone (preceded by the ⌀ symbol in the tolerance compartment) yields a 57.08% increase in usable tolerance area over traditional square coordinate tolerancing of the same nominal width. For inspection verification, coordinate deviations along orthogonal axes are converted to diametral position deviation via the formula: $\text{Actual Diametral Deviation} = 2 \times \sqrt{\Delta X^2 + \Delta Y^2}$. For non-cylindrical features like slots and tabs, bidirectional position tolerancing uses two single-segment feature control frames that omit the ⌀ symbol to define planar zones bounded by two parallel planes.

---

1. True Position & Theoretical Foundations (ASME Y14.5-2009 Section 7.2)

In modern manufacturing and engineering design, position tolerancing is the most widely applied geometric control. Unlike form tolerances (which never use datums) or orientation tolerances (which control angular relationships without locating), position controls the location, orientation, and relationship of features of size relative to one another or to established datums.

True Position Defined

True position is defined as the theoretically exact location of a feature of size (a hole, pin, slot, tab, or spherical feature) established by basic dimensions. True position has zero tolerance itself; it serves as the absolute target coordinate in 3D space about which a geometric tolerance zone is centered.

                    TRUE POSITION & BASIC DIMENSIONS

         Datum Plane B
              |  ◄─────────── [50.00] BASIC ───────────►
              |                                        │
              |         ┌──────────────────────────────┼────────────────┐
              |         │                              │                │
              |         │                              ▼                │
              |         │                     (True Position Axis)      │
              |         │                              │                │
              |         │                              │                │
              |         │                              │ [30.00] BASIC  │
              |         │                              │                │
              |         │                              │                │
              |         │                              ▼                │
              └─────────┴───────────────────────────────────────────────┴────
                                               Datum Plane C

The Role of Basic Dimensions & Datum Reference Frames

• Basic Dimensions: A basic dimension represents a theoretically exact value used to describe the size, profile, orientation, or location of a feature. On drawings, basic dimensions are enclosed in a rectangular box (e.g., [50]). Because basic dimensions carry no intrinsic tolerance, title-block plus-and-minus tolerances never apply to basic dimensions.
• Datum Reference Frame (DRF): Position tolerancing requires datums. A position feature control frame must reference one, two, or three datums to constrain the required degrees of freedom (up to three translations and three rotations) and locate the tolerance zone unambiguously in space.
• Rule #2 Application: Under ASME Y14.5-2009, Regardless of Feature Size (RFS) is the default condition for position tolerances and datum references if no material condition modifier (Ⓜ or Ⓛ) is indicated.

---

2. Cylindrical (Diametral) Tolerance Zones vs. Square Coordinate Tolerancing

Before geometric dimensioning and tolerancing, engineering drawings relied on coordinate (plus-and-minus) tolerances to locate hole centers (e.g., $X = 50.00 \pm 0.10$, $Y = 30.00 \pm 0.10$). This legacy approach suffers from three major functional flaws:

1. Square / Rectangular Tolerance Zones: Coordinate tolerancing generates a square or rectangular boundary for the feature center.
2. Tolerance Accumulation: Tolerances stack up across sequential coordinate chains.
3. Artificial Rejection of Functional Parts: Parts with equal clearance in all radial directions are rejected at the orthogonal extremes.

The 57.08% Usable Area Advantage

Consider a hole located by coordinate tolerances of $\pm 0.10\text{ mm}$ along the X-axis and $\pm 0.10\text{ mm}$ along the Y-axis:

• The coordinate tolerance zone is a square with side length $S = 2 \times 0.10 = 0.20\text{ mm}$.
• The total area of this coordinate square is: $\text{Area}_{\text{square}} = S^2 = (0.20\text{ mm})^2 = 0.0400\text{ mm}^2$
• The maximum permissible displacement in this square occurs at the four 45° corner diagonals: $r_{\text{corner}} = \sqrt{(0.10\text{ mm})^2 + (0.10\text{ mm})^2} = \sqrt{0.0200} \approx 0.1414\text{ mm}$

If the mating bolt or clearance assembly can function successfully when the hole center is displaced by $0.1414\text{ mm}$ at a 45° angle, then the hole should functionally be permitted to displace by that same radial distance ($0.1414\text{ mm}$) in any radial direction! A round hole mating with a round fastener has radial symmetry; it does not care whether a displacement occurs horizontally, vertically, or diagonally.

              COORDINATE SQUARE VS. DIAMETRAL CYLINDRICAL ZONE

                        +Y ▲
                           │   /‾‾‾‾‾‾‾‾‾‾‾‾‾‾\   ◄── Cylindrical Zone
                           │  /   ┌────────┐   \       (Diameter = 0.2828)
                    +0.10 ─┼─┼────│────────│────┼─
                           │ │    │   •    │    │
                     0.00 ─┼─┼────┼──(TP)──┼────┼─► +X
                           │ │    │        │    │
                    -0.10 ─┼─┼────│────────│────┼─     Square Zone
                           │  \   └────────┘   /   ◄── (0.20 x 0.20)
                           │   \______________/
                           │
                          ─┴──────┴────────┴──────
                                -0.10     +0.10

By converting this maximum functional radial displacement ($r = 0.1414\text{ mm}$) into a cylindrical tolerance zone:

• The diameter of the circumscribing cylindrical tolerance zone is: $D = 2 \times r_{\text{corner}} = 2 \times 0.1414\text{ mm} = 0.2828\text{ mm}$
• The area of this circular zone is: $\text{Area}_{\text{circle}} = \frac{\pi}{4} D^2 = \frac{\pi}{4} (0.2828\text{ mm})^2 \approx 0.06283\text{ mm}^2$
• Calculating the percentage increase in usable tolerance area: $\text{Ratio} = \frac{\text{Area}_{\text{circle}}}{\text{Area}_{\text{square}}} = \frac{\frac{\pi}{4} (2\sqrt{2} t)^2}{(2t)^2} = \frac{\frac{\pi}{4} (8t^2)}{4t^2} = \frac{2\pi}{4} = \frac{\pi}{2} \approx 1.5708$

$\text{Percentage Increase} = (1.5708 - 1) \times 100\% = 57.08\%$

By replacing a $\pm t$ coordinate tolerance with a diametral position tolerance of diameter $2\sqrt{2}t$, manufacturing gains 57% additional usable tolerance area without reducing assembly clearance or functional reliability. Conversely, if a cylindrical zone of diameter $2t$ (matching the width of the coordinate box) is used, the inspection zone is invariant in all directions, eliminating the directional bias of coordinate tolerancing.

---

3. Coordinate-to-Position Conversion Formulas

When inspecting features of size on Coordinate Measuring Machines (CMMs) or open-setup surface plates, measurements are recorded in Cartesian coordinates ($X, Y$). The quality engineer or inspector must convert these linear coordinate readings into the equivalent diametral position deviation to verify compliance with the feature control frame.

Step-by-Step Mathematical Conversion

1. Determine Coordinate Deviations from Basic Location: $\Delta X = X_{\text{measured}} - X_{\text{basic}}$ $\Delta Y = Y_{\text{measured}} - Y_{\text{basic}}$
2. Calculate True Radial Displacement ($r$): $r = \sqrt{\Delta X^2 + \Delta Y^2}$
3. Calculate Actual Diametral Position Deviation ($D_{\text{actual}}$): $D_{\text{actual}} = 2 \times r = 2 \times \sqrt{\Delta X^2 + \Delta Y^2}$
4. Evaluate Compliance:
   • Compare $D_{\text{actual}}$ to the total allowable position tolerance ($T_{\text{allowable}}$): $\text{Pass Condition: } D_{\text{actual}} \le T_{\text{allowable}}$

Worked Example: CMM Inspection Verification

An engineering drawing specifies a hole location with basic dimensions $X = 45.00\text{ mm}$ and $Y = 60.00\text{ mm}$. The feature control frame specifies: [ Position | Ø 0.25 | A | B | C ] (applied Regardless of Feature Size).

During CMM inspection, the actual center of the hole is probed at:

• $X_{\text{measured}} = 45.09\text{ mm}$
• $Y_{\text{measured}} = 59.93\text{ mm}$

Calculation:

1. $\Delta X = 45.09 - 45.00 = +0.09\text{ mm}$
2. $\Delta Y = 59.93 - 60.00 = -0.07\text{ mm}$
3. Radial deviation: $r = \sqrt{(0.09)^2 + (-0.07)^2} = \sqrt{0.0081 + 0.0049} = \sqrt{0.0130} \approx 0.1140\text{ mm}$
4. Actual diametral position deviation: $D_{\text{actual}} = 2 \times 0.1140\text{ mm} = 0.228\text{ mm}$
5. Evaluation: Since $0.228\text{ mm} \le 0.25\text{ mm}$, the hole location is in conformance.

Critical Note: Under traditional coordinate tolerancing of $\pm 0.08\text{ mm}$, this hole would have been erroneously scrapped because $\Delta X = 0.09\text{ mm}$ exceeds $0.08\text{ mm}$, even though its true radial position error is fully acceptable.

---

4. Bidirectional Position Tolerancing (ASME Y14.5-2009 Section 7.2)

While cylindrical tolerance zones (preceded by ⌀) are standard for cylindrical holes and pins, non-cylindrical features of size—such as rectangular slots, keyways, and tabs—frequently have different functional alignment requirements in their length and width directions.

                 BIDIRECTIONAL POSITION ON A RECTANGULAR SLOT

                           Datum B
                              │
       ◄─── [40.0] BASIC ────►│
       ┌──────────────────────┼────────────────────────┐
       │                      │                        │
       │         ┌────────────┼────────────┐           │
       │         │            │ (Center)   │           │ ▲
       │         │     ───────*───────     │           │ │ [25.0] BASIC
       │         │            │            │           │ │
       │         └────────────┼────────────┘           │ ▼
       └──────────────────────┴────────────────────────┴───────── Datum C
                               
         Width Direction (X):  `[ Position | 0.15 | A | B | C ]` (No ⌀)
         Length Direction (Y): `[ Position | 0.60 | A | B | C ]` (No ⌀)

Rules for Bidirectional Position Callouts

• Absence of Diameter Symbol (⌀): When controlling slots, tabs, or planar surfaces, the tolerance zone is not a cylinder. Therefore, the diameter symbol (⌀) must be omitted from the tolerance compartment.
• Planar Tolerance Zone Geometry: The tolerance zone consists of two parallel planes separated by the specified tolerance value, symmetrically centered on the true position basic center plane.
• Two Single-Segment Callouts: To control location in both orthogonal directions with different tolerances, two separate single-segment feature control frames are used:
  1. One FCF is associated with the width size dimension, controlling center plane displacement in the width direction.
  2. A second FCF is associated with the length size dimension, controlling center plane displacement in the length direction.
• Datum Precedence in Bidirectional Control: Both feature control frames typically reference the same primary, secondary, and tertiary datums, but the directional orientation of the parallel planes is governed by which feature dimension the frame is attached to.

---

5. Master Comparison Table: Coordinate vs. Position Tolerancing

| Attribute / Parameter | Coordinate Tolerancing (Plus/Minus) | Position Tolerancing (True Position) | | :--- | :--- | :--- | | | Tolerance Zone Geometry | Square or rectangular box | Cylindrical volume (for cylinders) or parallel planes (for slots) | | Zone Orientation | Locked to arbitrary coordinate grid lines | Locked to functional Datum Reference Frame (DRF) | | Usable Tolerance Area | Fixed square boundary ($S^2$) | 57.08% larger usable area ($(\pi/2) \times S^2$) for radial zones | | Material Condition Modifiers | Prohibited (strictly size-based) | Permitted (RFS default, Ⓜ for bonus, Ⓛ for wall thickness) | | Functional Gaging | Impossible (requires point-by-point CMM) | Directly inspectable via fixed-pin functional receiver gages | | Tolerance Stacking | High risk of cumulative stack-up | Eliminated via basic dimensions from common datums | | Syntax Marker | $\pm$ tolerance on coordinate dimension | Basic dimension ([ ]) + Feature Control Frame ([ ⌖ | ... ]) |

---

6. Common Exam Traps: Position Fundamentals

• Trap 1: Forgetting the Factor of 2 in Diametral Deviation: In CMM conversion problems, candidates frequently compute $r = \sqrt{\Delta X^2 + \Delta Y^2}$ and compare $r$ directly to the specified diameter tolerance. The radial displacement $r$ is only the zone radius; it must be multiplied by 2 to obtain the actual diametral deviation ($D = 2r$).
• Trap 2: Adding a Diameter Symbol (⌀) to Bidirectional Slot Controls: A drawing showing [ Position | Ø 0.2 | A | B ] applied to a slot width is a syntax error. Slots are bounded by two parallel planes; adding ⌀ indicates an impossible cylindrical zone.
• Trap 3: Applying Title Block Tolerances to Basic Dimensions: Basic dimensions are untoleranced references. Applying a title-block tolerance (such as $\pm 0.25$) to a boxed basic dimension is an outright exam error.
• Trap 4: Assuming Square Zones Allow More Variation: Candidates often mistakenly think square zones allow more variation because they have corners. In reality, the corners allow displacement along the 45° angle, but the cylindrical zone permits that same maximum displacement in all 360° directions, capturing 57% more acceptable parts.
• Trap 5: Confusing Single-Segment Bidirectional with Composite FCFs: Bidirectional tolerancing of a slot uses two distinct single-segment frames (one for width, one for length). It is not a composite frame; composite frames control pattern location in the upper segment and internal feature-to-feature orientation in the lower segment.